Pads in inner layers

Paxton Alsgaard schrieb:

I am making my first board with inner supply layers, and when I make the cam

files, the component pads are showin up in the inner layers. Since the

supply layers are inverted, this makes an area around the thru-holes with no

copper, and none of my power or ground connections are being made. How do I

keep the pads from showing up in my supply layers?

Probably you didn't set the NAME of the supply layers (or your supply

nets) correctly resp. matching each other.

Of course every pad that has another net/signal name is insulated in the

supply layer by the "annulus" symbols you noticed. Those pads that have

the same name will show a "thermal" symbol in the supply layer.

For details, see HELP LAYER (and/or the manual).

You might check your signal names with the SHOW command and look what

gets hightlighted. Also, INFO is a good help.

Tilmann

Tilmann,

Thank you for your time, I greatly appreciate the help. I have  checked the
names of all the layers and nets several times, and I think that  they are
correct. I don't know what I'm doing wrong. I have attached a  couple of
screen shots to clarify the issue. Help1 is the Eagle layout, and  Help2 is
the gerber files open in Gerbv, with only the ground layer,  silkscreen, and
drill data shown. You can see that the thermal symbol is  shown in the supply
layer in eagle, but when the CAM files are generated,  the pad shows up in
the supply layer as negative space. The oval pads on the  IC above C10 show
up as well.

Again, I appreciate your help. Thank  You,

Paxton

Well I solved the problem. It was fairly easy to fix, although not obvious to me at first. In the CAM Job, pads and vias were selected for each inner layer tab, which is why they were showing up on the inner layers. Duh, right? Deselecting those in the job gave me the following:

Looks good. I now had an inner layer clearance error, which was fixed by activating restring for the thermal isolate under the supply tab in DRC. The final result, below, gives no more errors.

I would like to thank you Tilmann for your help, and I hope that this thread can help others who may run into the same issue.

On 09/07/2010 01:16 PM, Paxton Alsgaard wrote:

Tilmann,

>

Thank you for your time, I greatly appreciate the help. I have  checked the

names of all the layers and nets several times, and I think that  they are

correct. I don't know what I'm doing wrong. I have attached a  couple of

screen shots to clarify the issue. Help1 is the Eagle layout, and  Help2 is

the gerber files open in Gerbv, with only the ground layer,  silkscreen, and

drill data shown. You can see that the thermal symbol is  shown in the supply

layer in eagle, but when the CAM files are generated,  the pad shows up in

the supply layer as negative space. The oval pads on the  IC above C10 show

up as well.

>

Again, I appreciate your help. Thank  You,

>

Paxton

>

  Image:help1.JPG

  Image:help2.JPG

>

Can't see the image in the newsgroup but from what you are describing I

think this could be the problem.

I never used supply layers but I think when using supply layers don't

include the pad's in the cam setup for that layer.

Paul R.

Paxton Alsgaard schrieb:

I have attached a couple of screen shots to clarify the issue.

Take care that if you are posting through the web interface at

element-14, none of your "attachments" are sent to the newsgroups.

Besides other bugs and limitations, this is one of the disadvantages of

that interface. You might consider directly accessing the newsgroups

with a newsreader.

Otherwise, you'd better place your files anywhere on the web and include

links in your post.

Anyway, thanks for letting us know you found the solution.

Tilmann