Actions
Forum Thread Details
  • Replies 2 replies
  • Subscribers 179 subscribers
  • Views 449 views
  • Users 0 members are here
Related

ULP problems - UL_PIN object's "net" attribute

autodeskguest

Hi all,

 

According to the help for the UL_PIN object,

 

The net data member returns the name of the net to which this pin is

connected (only available in a schematic context).

 

So, as I understand it, something like:

 

         S.parts(P) {

            if(P.name==find) {

               P.device.gates(G)

               {

                  G.symbol.pins(PIN)

                  {

                     printf("%s\t%s\n", PIN.name, PIN.net);

                  }

               }

            }

         }

 

ought to print a list of the pin names of a given device, and the nets

they're connected to. However, it doesn't. It prints the names, but all

the nets are just blank. This is the same on V4.16, V5.12 and V7.6

 

What am I doing wrong?

 

Cheers,

Rob

 

Parents

  • Hi Rob!

     

    You need to loop through a device's instances. For the entire schematic:

     

    schematic(SCH)

    {

        SCH.sheets(S)

        {

            S.instances(I)

            {

                if(I.name == find)

                {

                    I.gate.symbol.pins(PIN)

                    {

                        string s;

                        sprintf(s, "%s\t%s\n", PIN.name, PIN.net);

                        dlgMessageBox(s);

                    }

                }

            }

        }

    }

     

     

    Rene

     

     

     

     

Reply

  • Hi Rob!

     

    You need to loop through a device's instances. For the entire schematic:

     

    schematic(SCH)

    {

        SCH.sheets(S)

        {

            S.instances(I)

            {

                if(I.name == find)

                {

                    I.gate.symbol.pins(PIN)

                    {

                        string s;

                        sprintf(s, "%s\t%s\n", PIN.name, PIN.net);

                        dlgMessageBox(s);

                    }

                }

            }

        }

    }

     

     

    Rene

     

     

     

     

Children
  • in reply to autodeskguest

    On 21/10/16 21:10, René König wrote:

    Hi Rob!

     

    You need to loop through a device's instances. For the entire schematic:

     

    schematic(SCH)

    {

        SCH.sheets(S)

        {

            S.instances(I)

            {

                if(I.name == find)

                {

                    I.gate.symbol.pins(PIN)

                    {

                        string s;

                        sprintf(s, "%s\t%s\n", PIN.name, PIN.net);

                        dlgMessageBox(s);

                    }

                }

            }

        }

    }

     

     

    No luck with that. I got a syntax error on S.instances(I) and when I

    tried an extra layer:

     

         S.parts(P)

         {

            P.instances(I)

            {

     

    then I got no output at all.

     

     

    Ah... hang on...

     

    OK, so the problem is the instance isn't named right.

     

             SCH.sheets(S)

             {

                S.parts(P)

                {

                   if(P.name==find)

                   {

                      P.instances(I)

                      {

                         I.gate.symbol.pins(PIN)

                         {

                            printf("%s\t%s\n", PIN.name, PIN.net);

                         }

                      }

                   }

                }

             }

     

    seems to work. Thanks, Rene.

     

    (It does feel like a bug that the simpler form doesn't work, though)

     

    Cheers,

    Rob